Discover how to create a connection between the neck tube and the folding bracket in 3D modeling. This process includes creating new sketches, organizing files, creating a connector profile, adding 3D geometry, and making modifications to ensure a solid, functional design.
Key Insights
- The connection between the neck tube and folding bracket begins with organizing an array of sketches, including lower and upper ring profiles, and creating a new sketch for the connector profile.
- 3D geometry is applied to the connector profile through a series of processes including extrusion, shelling, and adding fillets. The connector is also hollowed out to ensure it is not a solid block of steel.
- Additional modifications are made, such as hiding the tube during the creation process and adding a pipe to prevent intersection with the tube. The final step involves activating the top level to see the completed connection between the scooter's front wheel and deck.
This lesson is a preview from our Fusion Certification Course Online (includes software & exam). Enroll in this course for detailed lessons, live instructor support, and project-based training.
Now we can create the connection between the neck tube and the folding bracket. And to do that, let's get organized because we're going to create yet another sketch and our sketches folder is starting to get kind of full. So open up our sketches folder, we have our tube path.
Then we have this sketch, we'll zoom in. We can see it's the profile for that lower ring. We're gonna call that ring lower profile.
Then our final unnamed sketch here is for that upper ring. We're gonna call that one ring upper profile. And with that, we're organized in our sketches folder.
We can go ahead and create a new sketch. We'll go to the solid area, create menu and create sketch. We want to select our construction plane as this neck center plane.
We'll select neck center and we're going to insert a sketch. We're gonna go up to the insert dropdown and we will select DXF. The plane has already been selected.
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It's our neck center. And now we need to select our DXF file. This is a course download and we want to save that to our computer.
And it's called Fusion 101 Neck Connector. DXF. We'll open that file and we'll notice it outlined here. There is that sketch and we'll go ahead and click okay. All right, it's called sketch four right now.
So let's go ahead and give that a name. We will call it connector profile. It's got our connector profile.
Let's zoom in a little closer there. We can see it connects right from the tube back to that folding bracket. And now we can give it some 3D geometry.
We're going to go ahead and click the finish sketch. And now we're going to go back to this create area and we want to select extrude. What do we want to extrude? We're going to select our profile here and the profile is our connector profile.
We'll have to select it visually. And for direction, we want to go with symmetric. And we'll pull this out.
What does Fusion want to do already? It wants to create a cut. We want to set the distance at 15 millimeters, but we don't want the cut. We want to swap that out for a new body because we want to create that connector piece looking just like that.
Once we've got it, we'll go ahead and click okay. So that's looking pretty good. We want to add a couple of things and it intersects right now with our tube.
So let's first go ahead and hide the tube. In our bodies folder, we can click the icon to hide that neck tube. So it's hidden.
And then we have this body is unnamed. We'll rename it. We'll call it connector.
And now we want to add some definition. Right now it's a solid hunk of steel and we want to hollow it out. Let's go ahead and do that first.
We'll go up to the modify panel and look for the shell command. We'll click on shell. And we want to click on this face that faces toward the tubes.
We'll click there. And in this menu, we have a couple of options. We have a sharp shell or a rounded shell.
We'll keep it as sharp. And our inside thickness, we want to call it three millimeters. And the direction is to the inside.
And what that does is shell this all out. It hollows everything out on the inside. Now we'll click okay.
And now we want to add some fillets. On the modify panel, we'll look for a fillet. And before we select anything, we want to make sure that tangent chain is turned on.
That means if we hover over one edge, it will continue to select all the edges that are tangent. We want to keep that checked. And then we want to click on the left overall edge, orbit around and click on the right overall edge.
With both of those edges selected, we want to now give them a radius and we'll go two millimeters. That looks pretty good. We will click okay.
Now the one thing that's missing is that this connector comes straight in and intersects with our neck tube. If we look inside of here, it doesn't work so well for our stem to come through because that connector is in the way. So let's keep that neck tube hidden for now.
And I'm going to unhide our tube path in my sketches folder. Sketches folder, tube path, unhide it. So I've got this line right here.
I can use that to create geometry to cut the curvature out of the connector. Now I can go to the create tab and go ahead and select pipe again. And now I'll click connect.
And now I will click on this line right here, the tube path line. And I want to set my section. If it was set to hollow, I want to uncheck the hollow box and I want to make sure it's set to circular and section size is 30.
Let's double check the objects to cut. It should only be cutting our connector, which is part of the neck component. So as long as it's only the connector, we're okay to click okay.
And it's been cut. You can see now it will no longer intersect the tube. Let's go ahead and do a little housekeeping.
Now we want to hide our tube path again and turn on our body neck tube. And with that, we have our neck. We can go ahead and activate the top level to see the result.
And that's looking pretty good. Our scooter front wheel is finally now connected to the deck with that neck. Great time to hit that save button.
