Master the art of creating a hub and rim in your design sketches. This article provides a detailed step-by-step guide on how to use Fusion to create a detailed hub and rim sketch, including how to use work planes, display settings, and change visual styles in your design.
Key Insights
- In Fusion design, you can create a hub and rim sketch by using work planes you've already used, such as the tire profile plane, which allows you to adjust display settings for clarity.
- While creating the hub and rim sketch, you can create detailed sketches by creating lines to specific lengths (such as a 15mm line to the right and a 20mm line straight up), creating rectangles and triangles, and deleting lines that are no longer needed.
- Once the sketches are complete, you can verify these are closed sketches by going back to display settings and selecting 'visual style', thereby enabling you to proceed to finish the sketch and create a revolve.
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Now that we have our tire, let's create our hub and our rim, and we'll do that with another sketch. So go back to create, create sketch. We're going to use a work plane we've already used before.
It's the tire profile plane. We'll select that as our work plane, and we'll zoom in tight to the bottom of the tire. Now we can't see through that tire very easily, so if we look at the bottom of our screen in Fusion, we have display settings.
We'll click that, open up visual style, and change it to wireframe. Now we can see right through the tire. We'll go to our line tool, and we'll zoom in a little bit tighter.
We can click right on the center bottom of the tire to begin our line, and draw to the right. We're going to draw 15 millimeter line, and click enter. We'll go back to our line tool, and click where we left off one time, and go straight up 20 millimeters.
20, enter. Now we want our base of our rim, so we'll click right where we left off, go straight to the left, and type in 30, enter. We have this line.
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We can delete the lines that got us there. So first this bottom line, select it, delete, and the right line, select, delete. That is the bottom of our rim.
Now we can draw up from here. Go back to our line tool. I'll click on the right side, and this one I want to go up four millimeters, so I'll type in four.
I want to create a rectangle here, a 30 × 4 rectangle. So I'll draw another line here to here, and then from there down. Click, and I have a rectangle.
Now we are used to those rectangles shading when they're all completed. This one did not shade. That's because we're in the wireframe mode, and so shading won't apply, but it is a sketch.
Now we want to create a triangle on top of our rectangle. Go back to our line tool, click right in the top center of that rectangle one time, move our mouse up, and we want to do three. Now we'll use the line command again to connect the top of our triangle to the left side, and then back again from the top of our triangle to the right side.
Now we can select and delete the lines that are interior that we no longer need, and there is our shape. We have the rim done. Now let's go and create the hub.
To create the hub, we need to locate the center of our wheel first. So let's create a line. We're going to start at the bottom right here at this origin point, maybe over to the right.
Make sure we're right here on this red axis, and it can be helped to kind of snap to a grid point as well. I'll click one time, move my cursor straight up, and type 100 and enter. Now we're up off the ground by 100 millimeters.
I can start the line command again, click the top, and then go to the left side. I might want to snap to that same grid point on the other side. So I'll click, and there is my line.
I'll hit escape to end the line command. I don't need this vertical line anymore, so I'll select it and delete it. This line is special.
It's the very center of our wheel. So I will right click on it and change it from a normal line to a construction line by selecting the normal construction line tool. I can also select it and hit X on my keyboard to toggle back and forth.
So there it is. It's a construction line now. I can also right click and change it to a center line.
No shortcut for that, but that works as well as a center line. Okay, let's draw the hub now. Let's go to our line command right here on the right side where the tire and that center line intersect.
I'm going to click and move my cursor straight down. How far? I'm going to go 2.5 and enter. That's because we're dealing with this five millimeter hole, so half of that is 2.5. Click my line here, start on the right side, go to the left, and this wants to be 30.
Enter. It's very similar to the rim. We're going to create a rectangle and then add a triangle on top, but it'll be a different shape.
This time, we're going to start right here. I'm going to go down. This time, seven millimeters, a little bit bigger rectangle.
Let's finish off that rectangle. There to there is 30 millimeters, and then back is another seven. So there is our rectangle.
We can delete this small 2.5 millimeter line. Now we want to draw the center of our triangle. We'll go to the middle of that bottom line, and we want to snap to the midpoint.
We'll click, drag our cursor down, and we'll type in three for three millimeters. Now we'll add the lines for our triangle. So the middle point to the right, and then middle point again to the left.
I don't need these internal lines. I will select them and click delete. All right.
So I've got my sketches. I've got my rim. I've got my hub, and I have my center line.
Now, if I want to verify that these are closed sketches, I can do that by going back to my display settings, visual style, and going back to shaded with visible edges only. And there they are. Still a little hard to see because everything is black in color, but we've got these shaded shapes.
They look pretty good. So once we're happy with our sketch, we will click our finish sketch button and click back to our home view. So there they are.
Now this time we will create by making a revolve. So I'll go to my create, and we will do a revolve this time. Now it wants to select our profiles first.
We'll select the bottom profile and the top profile. And our axis, we will select that. It can be that center line we created.
We'll click there. And notice the operation is join, and it's picking up the material from our tire, which is rubber. We don't want rubber for our hub and rim.
We want it to be a metal. We will swap the operation out to new body. And notice how now it is that steel color.
And we'll go ahead and click okay. Now we've got a little bit of housekeeping to do. We have that sketch.
It's called sketch three. We'll rename it to hub and rim. And then our body here, this will be the rim.
It's on the outside. And the one on the inside, we will call it hub. Perfect.
Now we have our tire, our rim, and our hub completed.
