Discover the technique of creating sliding locks by creating holes in two stems, stem A and stem B. Learn how to align these stems, create a tangent plane, and produce evenly spaced dots that serve as the center points of our holes.
Key Insights
- The process of creating sliding locks involves activating the top line of the browser to hide the wheel and select the hub hole for the fork, which in turn creates a tangent plane. The plane is then rotated to align with the center of the stems.
- The creation of evenly spaced dots that serve as the center points of the holes involves creating a sketch on the new plane, activating the line command, and creating a rectangular pattern. These dots ideally should be evenly spaced with three each on the upper and lower stem.
- The holes are created using the 'hole' function under the 'create' menu and selecting 'from sketch, multiple holes'. The width is set to eight millimeters and the process results in six holes that line up perfectly for both stems.
Note: These materials offer prospective students a preview of how our classes are structured. Students enrolled in this course will receive access to the full set of materials, including video lectures, project-based assignments, and instructor feedback.
Now that we have our two stems, stem B and stem A, we want to allow these stems to slide over each other and lock into place. And to do that, we're going to need to create some holes. Our first step is to go up to the top line of our browser and activate that top line.
That opens up everything, everything is active. And now we want to hide our wheel two. We don't want to see that for the moment.
And we want to go to our construct window and pull that down and find our tangent plane. Now we're going to zoom into our fork and we want to select right inside that hub hole for our fork, the left side of the fork in our screen here. We'll click that face and that creates a tangent plane.
Now we want to rotate it back and we want to go to negative 16. We might have to type it in, minus 16. We want that plane to align with the center of our stems.
So in this case, it'll be minus 16. If yours is flipped the other way, you might have to do a positive 16. With that set, we'll click okay.
Learn Fusion
- Nationally accredited
- Create your own portfolio
- Free student software
- Learn at your convenience
- Authorized Autodesk training center
And notice we get a new folder here. It's our top line construction and we have a generic plane. We'll call this stem center for holes.
And there's that plane. Let's make sure it's not selected. We'll click off into space.
Nothing is selected because this step is really important. We're going to create a sketch on this new plane and it will align our view to that plane. We have to select it one time.
It will rotate our view one time and we'll leave that view the way it is while we work. So let's go ahead and go up to the create area and select create sketch. We want to click on stem center for holes and notice our view rotate.
We are now in perfect alignment with our stem A and stem B. And that's great. We want to not touch the view because this is the view we want to work in. Now we want to activate our line command and we want to click one time right at our origin point.
We'll click there and then move our cursor to the left and we want to go 450. So type 450, enter. All right, that takes us partially up our stem and now we want to create a line there.
So create a line. We'll click right where we left off, click one time and we're going to go up 100 millimeters. It's an arbitrary amount because this is used just as an alignment guide for our holes.
So there's that 100 millimeter line. With that line, I can now select it and I want to go to the create menu with it selected and select rectangular pattern. Now we get the rectangular pattern window and we want to do a couple things.
First, our object, we should have that 100 millimeter line selected. For our directions, we'll click on select and click the line that points to the left. Now for our distribution, yours might be set to extent.
We want to change that to spacing. And let's go ahead and drag that arrow to the left now. We'll notice it's adding some spacing and we want to go to 50 millimeters.
And we also want to change our quantity to six. So six at 50. We'll notice we can do this visually or right here in our top menu here, we can change the quantity to six and distance to 50.
Now the quantity is for the other direction and it doesn't really matter what that's set to. We'll leave it alone, whatever yours says. And we want that distance to become zero because we don't want any lines in the other direction.
So with that, we'll go ahead and click okay. Going to think for a moment and now we have these spacing lines. Now we're not going to turn them into physical geometry.
They are just there for reference. We can select all of them by drawing a crossing window, right click and select normal construction. We'll just make those construction lines.
We also want this vertical line, a construction line as well. We'll select it one time, right click and go to normal construction. Now this is all simply for spacing.
And what our goal is, is we need to have these dots. These will become the center points of our holes. So essentially we want three dots down here on our lower stem and three dots on our upper stem.
If this is giving you grief, it's you're okay as long as you have three dots on the upper stem and three on the lower and ideally they'll be evenly spaced. With that, let's go ahead and click the finish sketch button. But let's not move our view for now.
It's okay to work right where we are. Let's go ahead and go to the create menu and look for the hole. There's a function called hole.
We'll click on that. And here in our window, we have placement options. The first is at a point, a single hole or from sketch.
And that's the one we want. We want from sketch, multiple holes. We'll click that.
And now we can click our sketch points. And we want to click all six of our sketch points here. We'll go down the line and select all six.
So it should say six selected. Now the extent, we can leave that at distance. And we can leave the other defaults for now.
If yours is set to depth at 20, that's fine. And the default typically is 118 on the degrees for the hole. That's essentially the drill point.
And we want to set the width to eight, eight millimeters. Now, before we click okay, now we can finally break our view. We'll go up to the home on our view cube and see what's going on.
We can orbit to the back. And notice we're getting holes right here on the backside. And that's fine.
That's not a problem. That's what we're looking for. We're not really looking for tapping into the hole.
We just want a hole all the way through. We can simply click on our extents, what's set to distance and click on all. And all will just make a hole without a tapping point.
We see we no longer have that drill tap. It's just a hole. And we want to set our size to eight millimeters.
And with that, we can go ahead and click okay. Now let's look at the results. Our end goal is to have our six holes.
And we'll notice that some of these holes are going through both STEM-A and STEM-B. What's interesting, let's go ahead and activate STEM-A. We'll notice that that operation is on the history for STEM-A.
So Fusion's pretty smart. It knows that these holes right here are for STEM-A. Now let's go ahead and activate STEM-B.
And we'll notice the same thing. Those holes also affect STEM-B. And with that, we've created a set of holes that line up perfectly for both STEMs.
Let's go ahead and reactivate the top line of our browser and click the save button.
